WO2022138056A1 - Dispositif de traitement d'informations et programme de traitement d'informations - Google Patents

Dispositif de traitement d'informations et programme de traitement d'informations Download PDF

Info

Publication number
WO2022138056A1
WO2022138056A1 PCT/JP2021/044340 JP2021044340W WO2022138056A1 WO 2022138056 A1 WO2022138056 A1 WO 2022138056A1 JP 2021044340 W JP2021044340 W JP 2021044340W WO 2022138056 A1 WO2022138056 A1 WO 2022138056A1
Authority
WO
WIPO (PCT)
Prior art keywords
program
code
information processing
function
machine tool
Prior art date
Application number
PCT/JP2021/044340
Other languages
English (en)
Japanese (ja)
Inventor
浩也 坂本
陽司 津久井
路彦 伊藤
Original Assignee
Dmg森精機株式会社
Priority date (The priority date is an assumption and is not a legal conclusion. Google has not performed a legal analysis and makes no representation as to the accuracy of the date listed.)
Filing date
Publication date
Application filed by Dmg森精機株式会社 filed Critical Dmg森精機株式会社
Publication of WO2022138056A1 publication Critical patent/WO2022138056A1/fr

Links

Images

Classifications

    • G—PHYSICS
    • G05—CONTROLLING; REGULATING
    • G05B—CONTROL OR REGULATING SYSTEMS IN GENERAL; FUNCTIONAL ELEMENTS OF SUCH SYSTEMS; MONITORING OR TESTING ARRANGEMENTS FOR SUCH SYSTEMS OR ELEMENTS
    • G05B19/00—Programme-control systems
    • G05B19/02—Programme-control systems electric
    • G05B19/18—Numerical control [NC], i.e. automatically operating machines, in particular machine tools, e.g. in a manufacturing environment, so as to execute positioning, movement or co-ordinated operations by means of programme data in numerical form
    • G05B19/4093—Numerical control [NC], i.e. automatically operating machines, in particular machine tools, e.g. in a manufacturing environment, so as to execute positioning, movement or co-ordinated operations by means of programme data in numerical form characterised by part programming, e.g. entry of geometrical information as taken from a technical drawing, combining this with machining and material information to obtain control information, named part programme, for the NC machine

Definitions

  • the present invention relates to an information processing device and a program.
  • Patent Document 1 discloses a technique for automatically optimizing the positioning path of CL (Cutter Location) data generated by CAM (Computer Aided Manufacturing).
  • CL data is generated not only in the format standardized by ISO (International Organization for Standardization) but also in a unique format different for each CAM manufacturer.
  • the present invention An information processing device that processes programs executed by the numerical control device of a machine tool. Delete or ignore the preset function code of the function codes whose functions are not specified in ISO 6983-1: 2009 or JIS B 6315-1: 2013 from the program before processing, and before processing An information processing device including an information processing unit that detects a starting point code that is a starting point among a plurality of codes included in a program, performs a process of adding an additional code corresponding to the starting point code, and generates a processed program. Is to provide.
  • the present invention also provides an information processing device, a machine tool, a program, and the like.
  • the information processing apparatus 100 as the first embodiment of the present invention will be described with reference to FIG.
  • the information processing apparatus 100 is an apparatus for generating a machining program 130 used in the numerical control device 120 based on the machining program 150 generated in the CAM apparatus 140 as a computer-aided manufacturing system.
  • Examples of the machining program 150 include an NC (Numerical Control) program.
  • the information processing apparatus 100 includes a code filter unit 101, a machining program interpretation unit 102, an optimization processing unit 103, and a storage unit 104.
  • the code filter unit 101 performs filtering to delete non-standardized codes from a plurality of codes included in the machining program 150 generated by the CAM device 140.
  • the machining program interpretation unit 102 interprets a plurality of codes included in the filtering program 160, respectively.
  • the result of interpreting the machining program 160 may be expressed in any format.
  • it may be in the form of CL data as tool path data described by APT (automatically programmed tools) or internal data of the information processing apparatus 100.
  • APT is a programming language developed for numerical control of machine tools, and can automatically determine tool paths and machining procedures based on the shape of machine parts to be manufactured.
  • EXAPT extended subset of APT
  • the machining program interpretation unit 102 may output a machining program in which the non-standardized code (not deleted) included in the machining program 160 is replaced with the standardized code as an interpretation result.
  • the optimization processing unit 103 executes the optimization processing on the result of the interpretation in the machining program interpretation unit 102. Specifically, the code included in the machining program 150 is updated according to the specifications of the machine tool 110 and the numerical control device 120 to generate the optimized machining program 130. The optimization processing program 130 subjected to the optimization processing is transmitted to the numerical control device 120.
  • Various program modules 141 are stored in the storage unit 104.
  • a processor (not shown) realizes the functions of the code filter unit 101, the machining program interpretation unit 102, and the optimization processing unit 103 by executing various program modules 141.
  • the storage unit 104 further stores the code list 142 of the non-standardized code.
  • the code filter unit 101 deletes at least a part of the non-standardized code, and then proceeds to the interpretation by the machining program interpretation unit 102.
  • the optimization function peculiar to the machine tool and the numerical control device can be automatically added to the machining program without depending on the type of the CAM device, and the function of the machine tool and the numerical control device can be fully utilized. be able to.
  • the machining program after filtering is interpreted by the code filter unit 101, the development load of the machining program interpretation unit can be reduced.
  • the function of the information processing apparatus 100 may be mounted inside the machine tool 110.
  • the information processing apparatus 200 as the second embodiment of the present invention will be described with reference to FIG.
  • the information processing device 200 is a device for generating an NC program 230 as a machining program used in the numerical control device 220.
  • the numerical control device 220 is a device that numerically controls machining in the machine tool 210, and includes an NC interpreter 221 that interprets the NC program 230 and a command output unit 222 that outputs a control command to the machine tool 210.
  • Examples of the machine tool 210 include a machine that adds additive manufacturing to the work, a machine that applies subtractive manufacturing to the work, a machine that irradiates light such as a laser, and the like. Specifically, like lathes, drilling machines, milling machines, milling machines, gear cutting machines, grinding machines, multi-axis machines, laser machines, laminating machines, etc., numerically controlled based on the NC program, metals, Any machine may be used as long as it is a machine that performs various processing such as turning, cutting, drilling, grinding, polishing, rolling, forging, bending, molding, fine processing, and laminating processing on a work such as wood, stone, and resin. Further, the machine tool may have a measuring function, or may be configured to be able to measure the dimensions of the work using a measuring instrument such as a touch probe or a camera.
  • a measuring instrument such as a touch probe or a camera.
  • the machine tool 210 is, for example, a 3-axis machine tool, and includes a spindle motor 211 and a feed shaft motor 212 as machine elements.
  • the spindle motor 211 rotates the tool, and the feed shaft motor 212 linearly moves the table in the X and Y axis directions and linearly moves the tool or the table in the Z axis direction via a ball screw or the like.
  • the machine tool 210 may of course be a 5-axis machine tool.
  • the spindle motor servo controller 213 controls the spindle motor 211 based on a control command from the command output unit 222.
  • the feed shaft motor servo controller 214 controls the feed shaft motor 212 based on a control command from the command output unit 222.
  • the information processing device 200 includes an NC program acquisition unit 201, a code filter unit 202, an NC interpreter 203, an APT conversion unit 204, an optimization processing unit 205, a program transmission unit 206, and a storage unit 207.
  • the NC program acquisition unit 201 acquires the NC program 250 generated by the CAM device 240.
  • the CAM device 240 has a main processor unit 241 and a post processor unit 242.
  • the main processor unit 241 generates CL data 243 based on the shape data acquired from the CAD (Computer-Aided Design) device 260.
  • the post processor unit 242 generates the NC program 250 from the CL data 243.
  • the code filter unit 202 reads out a list of codes that are not compliant with ISO4343: 2000 stored in the storage unit 207 among the codes included in the machining program, and deletes them from the NC program.
  • the standard code defined in ISO4343: 2000 is a code for NC control such as shaft position and feed rate, PLC (Programmable Logic Controller) control such as gripping of a work and on / off of coolant. These are the basic control commands that can be interpreted by any numerical controller.
  • the NC interpreter 203 interprets each of a plurality of codes included in the filtered NC program.
  • the NC interpreter 203 realizes the same function as the NC interpreter 221 included in the numerical control device 220.
  • the APT conversion unit 204 performs inverse conversion from the interpreted NC program to the CL data described in APT. Normally, the post processor unit 242 performs the conversion from APT to NC in general, but the APT conversion unit 204 performs the inverse conversion from NC to APT.
  • the optimization processing unit 205 generates an NC program 230 optimized for the CL data described in APT.
  • the optimization processing unit 205 deletes unnecessary codes that are unnecessary for the machine tool 210 or the numerical control device 220, and adds a function code that realizes a function unique to the machine tool 210 or the numerical control device 220, at least one of them. Is executed in the machining program 250.
  • the program transmission unit 206 transmits the optimized NC program 230 to the numerical control device 220.
  • the optimization process has advantages for machining such as shortening of machining time, improvement of machining accuracy, saving of electric power and coolant, efficient removal of chips, efficiency improvement by visualization of process control, measurement processing, etc. It is a concept that includes all the processes that bring about. Specifically, examples of the optimization process include, but are not limited to, the following (1) to (4).
  • machining accuracy and machining time are optimized by specifying the desired machining mode. be able to.
  • A) Time priority mode A mode in which shortening of machining time is given top priority. Used when the required accuracy is low such as roughing.
  • B) Intermediate mode A mode between the time priority mode and the accuracy priority mode. Used for semi-finishing, etc., where high accuracy and short time are required.
  • Accuracy highest priority mode A mode in which machining accuracy is further prioritized over accuracy priority mode.
  • the storage unit 207 stores a program module that realizes an NC program acquisition unit 201, an NC interpreter 203, an APT conversion unit 204, an optimization processing unit 205, and a program transmission unit 206. Further, the storage unit 207 stores the command table and machine tool information in addition to the above-mentioned optimization processing information.
  • the command table is a table showing the correspondence between the commands and arguments of the standardized format and the commands (NC code) of the NC program.
  • the machine tool information is information about various machine tools of different machine tool manufacturers and models, such as machine origin, model stroke length, machine-specific command G code, M code (Mxx, Mxy), etc. It may contain the following information: (1) Model number of machine tool (2) Option information (number of turrets, spindle diameter, servo, type and presence of chip conveyor, type and presence of measuring device) (3) Usable tool types (eg drill, end mill) (4) Magazine pot number and pot number
  • FIG. 3 is a diagram conceptually explaining the flow of processing from the CAM device 240 to the machine tool 210.
  • the model is input in step S301, the machining shape is defined in step S302, and then the process design (cutting condition setting) is performed in step S303. Further, in step S304, CL data is generated based on the process design.
  • CL simulation is performed in step S305 and it is confirmed whether or not interference occurs in the path of the tool, NC program is generated from CL data in S306.
  • the information processing apparatus 200 filters and deletes the non-standardized code in step S307, interprets the received NC program in step S308, and optimizes the NC program in step S309. Specifically, regarding cutting, standardization of cutting force and tool feed, and regarding AM (Additive Manufacturing), stacking conditions, stage feed, laser output, powder supply amount, etc., or measurement functions are optimized, and the CAM device 240 is used. Add code to the NC program. After that, in the machine tool 210, actual machining is performed in step S310.
  • AM Advanced Manufacturing
  • FIG. 4 illustrates that the information processing apparatus 200 interprets and optimizes different types of NC programs 250a to 250c generated by the respective post processor units 242a to 242c by the CAM apparatus 240a to 240c of different vendors. It is a conceptual diagram to be processed. As shown in FIG. 4, the optimization function peculiar to the machine tool or the numerical control device can be automatically added to the NC program without depending on the type of the CAM device. As a result, the functions of the machine tool and the numerical control device can be fully utilized. For example, it is possible to shorten the processing time, improve the surface quality, save electric power and coolant, efficiently remove facets, and improve efficiency by visualizing process control.
  • the code filter unit 202 of the present embodiment has decided to filter and delete the non-standardized code, but the present invention is not limited to this.
  • the configuration may be such that the user can select from the following two options. It is desirable that the GM code filter can be edited by the machining operator. 1. Output as it is 2. Delete the code in the GM code filter
  • G0, G1, G2, and G3 have a common G code for all CAM devices (specified by ISO), but the optimization processing unit 204 uses such an ISO compliant G code. , Gives an optimization function.
  • a setting unit for setting whether or not to delete a plurality of types of non-standardized codes from the machining program is further provided, and the code filter unit 202 filters the machining program according to the setting contents in the setting unit. You may.
  • FIGS. 5A and 5B are diagrams showing specific examples from filtering to optimization of NC programs.
  • the code filter unit 202 deletes the ISO non-compliant code for the NC program example 250a output from the post processor unit 242a of the CAM device 240a.
  • ISO non-compliant G-codes and M-codes are recorded in the code list in advance.
  • G code and M code that do not exist in the code list are output to NC interpreter 203 as they are.
  • the NC interpreter 203 gives the interpretation result 501 to the NC program.
  • FIGS. 5A and 5B are merely conceptually shown, and do not mean that data is added in Japanese in this way.
  • the optimization processing unit 205 analyzes the interpretation result 501 and inserts a cutting mode setting code 502 called G332 immediately before the cutting start code G01 to optimize the machining before the cutting start.
  • G332 is a code for selecting the machining mode (cutting mode) of the above-mentioned (a) to (d). Specifically, in the NC program, any one of "G332R1", “G332R2", “G332R3”, and “G332R4" is inserted immediately before the cutting start code G01.
  • the arguments R1 to R4 are set in the following cases, respectively.
  • R1 Set at the time of rough machining (time priority mode)
  • R2 Set at the time of semi-finishing (intermediate mode)
  • R3 Set at the time of finishing (precision priority mode)
  • R4 User manually sets only when he / she wants to set (precision top priority mode)
  • G332 is a code that depends on the vendor of the numerical control device 220, and realizes optimization according to the numerical control device 220. Specifically, when the NC program 250a is inversely converted by the NC interpreter 203 to optimize the APT format CL data generated by executing a predetermined script, and then the NC program is converted to the NC program again. , G332 is inserted before G01. As another method, the optimization macro that searches for G01 and inserts G332 immediately before G01 may be executed while the NC program 250a remains. In this case, it is preferable to have a table in which the code to be inserted (for example, G332) and its position (for example, immediately before G01) are associated with each other.
  • the code to be inserted for example, G332
  • its position for example, immediately before G01
  • the NC program 230a to which the machining conditions are given is output to the numerical control device 220.
  • a predetermined code is deleted by the code filter unit 202 with respect to an example 250a of the program before processing output from the post processor unit 242a of the CAM device 240a.
  • the predetermined G code and M code are recorded in the code list in advance. G code and M code that do not exist in the code list are output to NC interpreter 203 as they are.
  • the NC interpreter 203 imparts an interpretation result 501 to the processed program.
  • the information processing apparatus 200 deletes or ignores the preset function code among the function codes whose functions are not specified in ISO 6983-1: 2009 or JIS B 6315-1: 2013 from the program before processing. (Comment out) Process. Then, it is provided with an information processing unit that detects a starting point code that is a starting point among a plurality of codes included in the program before processing, performs a process of adding an additional code corresponding to the starting point code, and generates a program after the processing. ..
  • JIS B 6315-1 2013
  • M07 to M09 do not have a function description in JIS B 6315-1: 2013, but include codes specified by other ISOs. If it is M07, it is described as "Refer to ISO / TR 6983-2.”
  • Codes whose functions are not specified in JIS B 6315-1: 2013 are G05, G07, G50 to G52, G100 to G999, etc. This G code is numbered in JIS B 6315-1: 2013, but the function is not specified.
  • codes whose functions are not specified in JIS B 6315-1: 2013 include codes that are not described in JIS B 6315-1: 2013 such as M51 and M59.
  • An example of the starting code is G01, and the additional code corresponding to G01 is G332, which is added before G01.
  • NC programs having different output positions and output codes can be similarly supported, and ISO-compliant NC codes can be interpreted. It is possible to generate and output an NC program with machining conditions.
  • G84 is a code whose function is not specified in JIS B 6315-1: 2013, and the function can be set for each numerical control device manufacturer. For example, it is assumed that maker A and maker B set G84 as a tapping cycle. The code filter unit 202 may delete or ignore this G84, but may leave it. Even if the function is not specified in ISO 6983-1: 2009 or JIS B 6315-1: 2013, it is possible to leave a specific code in which a function common to many manufacturers is set. Specifically, if the acquired CL data contains information that identifies the G84 and the numerical control device manufacturer, it may be converted into an NC program corresponding to the G84 of that manufacturer.
  • G84 may be used as a starting point code. That is, the code to be deleted or ignored because the function is not specified in ISO 6983-1: 2009 or JIS B 6315-1: 2013 may be the same as the starting code.
  • the origin code may be deleted in the output NC program after functioning as the origin.
  • FIG. 6 is a diagram for explaining the configuration of the information processing apparatus 600 according to the present embodiment.
  • the information processing apparatus 600 according to the present embodiment is different from the second embodiment in that it has a standardized CL data acquisition unit 601 and an NC program generation unit 602. Since other configurations and operations are the same as those in the second embodiment, the same configurations and operations are designated by the same reference numerals and detailed description thereof will be omitted.
  • a CL data standardization unit 644 that generates standardized CL data 645 with standardization information added to the CL data 643 output from the main processor unit 641 can be incorporated.
  • the "standardized information” is information based on a rule defined between a plurality of output devices such as a CAM device and a numerical control device.
  • the CL data standardization unit 644 identifies the unique control information contained in the CL data and generates standardized CL data 645 labeled in a standardized format corresponding to the unique control information.
  • the standardized CL data acquisition unit 601 of the information processing apparatus 600 acquires the standardized CL data 645, and the NC program generation unit 602 generates an NC program 630 based on the NC code and CL data corresponding to the standardization information.
  • machining process information 632 and NC macro 633 linked with the CL data standardization unit 644 can be added to the NC program 630 generated in this way.
  • specific control commands including the following specific control information can also be incorporated into the NC program 630.
  • A "Specific control information of the numerical control device” originally implemented by the numerical control device manufacturer of the machine tool.
  • B "Machine tool specific control information” originally implemented by the machine tool manufacturer
  • C "Specific control information of the machine tool user” independently implemented by the machine tool user.
  • (a) specific control information of the numerical control device includes the following.
  • Model number of numerical control device example: RPFK
  • Numerical control device manufacturer's custom macro Tapping cycle (TAP), G84XYZRPFK (manufacturer A), G84XYZPF, R00, I, J, L (manufacturer B)
  • Model number of machine tool (example: MORI) (2) Custom macro of machine tool manufacturer Example: Macro related to drill corresponding to the model number of machine tool (G432 etc.)
  • unique control information that can be set by the user of the machine tool includes the following.
  • Drilling cycle pattern example: CYCLE
  • Custom macros for machine tool users Example: Macros that correspond to the drilling cycle pattern (CYCLE) (G65P1000, etc.)
  • standardized CL data 645 is generated using standardized information based on the rules defined between the CAM device and the numerical control device, such as a standardized format for standardizing the specifications. Generated. That is, in the present embodiment, the specific control information is information such as custom macros, machining process information, etc. other than the information specified in ISO4343: 2000.
  • NC macro 633 which is one of the unique control information, is a program for extending G code and M code.
  • the NC macro 633 allows each machine tool manufacturer, machine tool maker, and machine tool user to implement their own unique functions (Gxx, Gxy, Mxx, Mxy, etc.).
  • the machining process information 632 which is one of the unique control information, is additional information for grasping the process management and various machining information by the HMI 610 and realizing the function for the purpose of work efficiency and traceability.
  • the HMI 610 is an application program for operating a machine tool and an application program for monitoring the state of the machine tool, and can be mounted on a tablet, a smartphone, or the like. Therefore, by visualizing various data in the HMI, the operability of the machine tool is improved.
  • the unique control information of the numerical control device (b) the unique control information of the machine tool, and (c) the unique control information of the user of the machine tool are not necessarily all required. Depending on the type of work and the machining method, it may be sufficient to generate the NC program in consideration of at least one or two unique control information.
  • the standardized format which is one of the standardized information, includes a command name and an argument name that can be specified by the command, and is stored in advance in the information processing apparatus 600.
  • a command name indicating the measurement function
  • an argument "FIN” indicating finishing processing
  • an argument "ROUGH” indicating rough processing
  • the PLC (programmable logic controller) 620 can be controlled by the NC macro 633, which is a control peculiar to the machine maker.
  • the information processing device 600 may be configured to display the function selection dialog 700 as shown in FIG. 7 on the display device so that the user can select the optimization process.
  • the NC program generation unit 602 outputs an NC program that has been optimized by the user. It is converted into the NC program which has been subjected to the optimization processing selected in the standardization correspondence display part 801.
  • the standardized CL data includes data related to the movement (operation link) that connects operations, but depending on the CAM model, the output CL data may not include such data. be. Therefore, the NC program generation unit 602 may add an operation link.
  • the NC program generation unit 602 may add an operation link. For example, in the operation link selection unit 801 of the function selection dialog 700 as shown in FIG. 8, it is also possible to generate an NC program including a path selected by the user. With this configuration, the user can use the optimum path generation function without depending on the CAM model.
  • FIG. 9 and 10 are diagrams showing an example of optimizing an NC program.
  • the CAM devices 640a to 640c of the companies A, B, and C are provided with the CL data standardization function and the CAD data is taken in, they are labeled in the standardized format (PROCMOD / FIN) that specifies the finishing process.
  • the created CL data 645 is output.
  • the information processing apparatus 600 reads the NC code (G915H42) corresponding to the standardized format (PROCMOD / FIN) from the command table 1001, reflects it in the NC program, and outputs it as an optimized NC program 630.
  • the measurement function is automatically turned on only in finish machining and the measurement function is automatically turned off in rough machining.
  • the NC program is optimized to correspond to the extended function by the user.
  • a high-speed deep drilling cycle G73 is selected from the fixed cycles of the G code.
  • G73 high-speed deep drilling cycle
  • standardized formats such as "DRILL1" and "DRILL2" that indicate the extended function by the user are defined in advance in the command table, and the corresponding NC code is left blank (reserved state). Then, the custom macro (G65P1000) to be called is additionally implemented in the blank corresponding to "DRILL1".
  • the information processing apparatus 600 that has received the CL data 645 reads the NC code (G65P1000) corresponding to the standardized format from the command table 1101, reflects it in the NC program, and outputs it as the optimized NC program 630.
  • the custom macro created by the user is called and the drilling is executed.
  • the NC program can be optimized to correspond to the extended function by the user.
  • a framework for generating a post processor that incorporates an optimization function has been constructed.
  • a standardized APT can be constructed and many optimization functions can be realized based on the generated standardized CL code.
  • the information processing device 600 functions as a common post processor that does not depend on the CAM device or the numerical control device, and the optimization function can be realized.
  • the optimization function which conventionally had to be implemented individually for each machine, can be used as a POST standard function, and the burden on the machine tool user can be reduced.
  • NC programs have already been standardized by ISO, but other machine manufacturer-specific controls can also be standardized and optimized.
  • CL data standardization unit 644 By standardizing the CL data in the CL data standardization unit 644, various optimization functions can be used in the NC program generation unit 602.
  • the present invention may be applied to a system composed of a plurality of devices, or may be applied to a single device. Further, the present invention is also applicable when an information processing program that realizes the functions of the embodiment is supplied to a system or an apparatus and executed by a built-in processor.
  • the technical scope of the present invention includes a program installed in the computer, a medium containing the program, a server for downloading the program, and a processor for executing the program. ..
  • at least a non-transitory computer readable medium containing a program that causes a computer to execute the processing steps included in the above-described embodiment is included in the technical scope of the present invention.
  • it is an information processing method for generating a machining program used in a numerical control device for controlling machining in a machine tool.
  • a code filter step that filters to remove non-standardized code from multiple codes contained in a machining program generated in a computer-aided manufacturing system.
  • a machining program interpretation step that interprets a plurality of codes included in the machining program filtered by the code filter step, respectively.
  • An optimization processing step that optimizes the code included in the machining program according to the interpretation result of the machining program interpretation step to generate a new optimized machining program, and Information processing methods including An information processing program that generates a machining program used in a numerical control device that controls machining in a machine tool.
  • a code filter step that filters to remove non-standardized code from multiple codes contained in a machining program generated in a computer-aided manufacturing system.
  • a machining program interpretation step that interprets a plurality of codes included in the machining program filtered by the code filter step, respectively.
  • An optimization processing step that optimizes the code included in the machining program according to the interpretation result of the machining program interpretation step to generate a new optimized machining program, and
  • An information processing program for causing a computer to execute an information processing program is also included in the technical scope of the present invention.

Landscapes

  • Physics & Mathematics (AREA)
  • Engineering & Computer Science (AREA)
  • Geometry (AREA)
  • Human Computer Interaction (AREA)
  • Manufacturing & Machinery (AREA)
  • General Physics & Mathematics (AREA)
  • Automation & Control Theory (AREA)
  • Numerical Control (AREA)

Abstract

L'invention concerne un dispositif de traitement d'informations pour traiter un programme qui est exécuté par un dispositif de commande numérique d'une machine-outil, le dispositif de traitement d'informations comprenant une unité de traitement d'informations qui effectue un traitement pour supprimer ou ignorer, à partir d'un programme avant traitement, un code de fonction de réglage prédéfini parmi des codes de fonction dont les fonctions ne sont pas spécifiées par la norme ISO 6983-1:2009 ou JIS B 6315-1:2013, détecte un code d'origine qui est une origine d'une pluralité de codes inclus dans le programme avant traitement, effectue un traitement pour ajouter un code supplémentaire correspondant au code d'origine et génère un programme après traitement.
PCT/JP2021/044340 2020-12-24 2021-12-02 Dispositif de traitement d'informations et programme de traitement d'informations WO2022138056A1 (fr)

Applications Claiming Priority (2)

Application Number Priority Date Filing Date Title
JP2020215739A JP6987960B1 (ja) 2020-12-24 2020-12-24 情報処理装置
JP2020-215739 2020-12-24

Publications (1)

Publication Number Publication Date
WO2022138056A1 true WO2022138056A1 (fr) 2022-06-30

Family

ID=79239695

Family Applications (1)

Application Number Title Priority Date Filing Date
PCT/JP2021/044340 WO2022138056A1 (fr) 2020-12-24 2021-12-02 Dispositif de traitement d'informations et programme de traitement d'informations

Country Status (2)

Country Link
JP (1) JP6987960B1 (fr)
WO (1) WO2022138056A1 (fr)

Families Citing this family (1)

* Cited by examiner, † Cited by third party
Publication number Priority date Publication date Assignee Title
JP7301486B1 (ja) 2021-12-22 2023-07-03 Dmg森精機株式会社 情報処理装置およびプログラム

Citations (6)

* Cited by examiner, † Cited by third party
Publication number Priority date Publication date Assignee Title
JPS6419412A (en) * 1987-07-15 1989-01-23 Toyota Motor Corp Feed speed controller
JPH04365538A (ja) * 1991-05-09 1992-12-17 Amada Co Ltd Ｎｃプログラムの適正化方法
JPH10320027A (ja) * 1997-05-15 1998-12-04 Fanuc Ltd 数値制御装置
JP2005149194A (ja) * 2003-11-17 2005-06-09 Honda Motor Co Ltd ソースプログラム変換システム
JP2006293744A (ja) * 2005-04-12 2006-10-26 Fanuc Ltd プログラム変換装置
JP2009053736A (ja) * 2007-08-23 2009-03-12 Fanuc Ltd 工作機械によらないｎｃ指令を入力する数値制御装置および加工方法

Patent Citations (6)

* Cited by examiner, † Cited by third party
Publication number Priority date Publication date Assignee Title
JPS6419412A (en) * 1987-07-15 1989-01-23 Toyota Motor Corp Feed speed controller
JPH04365538A (ja) * 1991-05-09 1992-12-17 Amada Co Ltd Ｎｃプログラムの適正化方法
JPH10320027A (ja) * 1997-05-15 1998-12-04 Fanuc Ltd 数値制御装置
JP2005149194A (ja) * 2003-11-17 2005-06-09 Honda Motor Co Ltd ソースプログラム変換システム
JP2006293744A (ja) * 2005-04-12 2006-10-26 Fanuc Ltd プログラム変換装置
JP2009053736A (ja) * 2007-08-23 2009-03-12 Fanuc Ltd 工作機械によらないｎｃ指令を入力する数値制御装置および加工方法

Also Published As

Publication number Publication date
JP6987960B1 (ja) 2022-01-05
JP2022101268A (ja) 2022-07-06

Similar Documents

Publication Publication Date Title
JP6868161B1 (ja) 情報処理装置、情報処理方法および情報処理プログラム
JP5414948B1 (ja) 数値制御装置
KR100766310B1 (ko) Ｇ 코드로부터 ｓｔｅｐ－ｎｃ 파트 프로그램으로 변환하는 방법 및 기록매체
JP5143005B2 (ja) 機械における加工プロセスの最適化のための方法
US20100138018A1 (en) Method for producing a parts program
CN106886197B (zh) 控制机器实施加工的方法及其装置和应用
CN107203188A (zh) 用于以优化的加工时间在机床中加工工件的方法
CN111258272A (zh) 加工参数调整系统及加工参数调整方法
WO2022138056A1 (fr) Dispositif de traitement d'informations et programme de traitement d'informations
CN110376962B (zh) 设定装置和计算机可读介质
JP7177905B1 (ja) 情報処理装置
WO2022138055A1 (fr) Dispositif de traitement d'information et programme de traitement d'information
JP7301486B1 (ja) 情報処理装置およびプログラム
KR101108211B1 (ko) 복합선반용 파트프로그래밍 장치 및 복합 공정간 동기화 프로그램 생성방법
JP6935606B1 (ja) 情報処理装置および情報処理プログラム
WO2023120391A1 (fr) Dispositif de traitement d'informations et programme générant un premier programme nc et convertissant un second programme nc
US9904277B2 (en) Numerical controller configured for operation based on tabular data
WO2022030485A1 (fr) Dispositif d'aide au développement de postprocesseur, système d'aide au développement de postprocesseur et procédé exécutable par ordinateur
JP7057593B1 (ja) Ｃｎｃ装置の加工プログラム生成用プログラム及びｃｎｃ装置用の加工プログラム生成方法
Broue et al. Feature-oriented programming interface for an autonomous production cell
EP3876050A1 (fr) Système de support de traitement
KR100398004B1 (ko) 수치제어 공작기계의 지-코드 생성방법
Katarína THE METHODS OF NC PROGRAM CREATING
Chatelain et al. Productivity assessment from advanced integration of canned cycles to CAD/CAM software
Brouër et al. Feature-oriented programming interface of an autonomous production cell

Legal Events

Date Code Title Description
121 Ep: the epo has been informed by wipo that ep was designated in this application

Ref document number: 21910208

Country of ref document: EP

Kind code of ref document: A1

NENP Non-entry into the national phase

Ref country code: DE

122 Ep: pct application non-entry in european phase

Ref document number: 21910208

Country of ref document: EP

Kind code of ref document: A1

NENP Non-entry into the national phase

Ref country code: JP